Re: [SI-LIST] : Parallel single-ended traces routed to achieve 35 Ohm controlledimpedance

About this list Date view Thread view Subject view Author view

From: Michael Nudelman (mnudelman@tellium.com)
Date: Tue Oct 31 2000 - 14:45:01 PST


Ken,

> Salvador,
> .......One of the obvious problems you
> will have is modulated Zo going from 70 to 35. Your acceptance function
> will only be 0.5, so you will only see a little over half the voltage at the
> receiver.

Well, this is not entirely true. I did not watch the whole discussion, and maybe
there are some initial conditions/driver data involved, but in general case for
a strong driver you'll see more than half and for whimpy one - less than half.

BUT - even if it is half-signal - if it is point-to-point trace with no end
termination, than your half-signal will double at the end and you are OK.

> Paralleling two TL's isn't like paralleling two resistors.

Well, yes it is. TL for a driver is nothing but a resistor.

> All
> you will add with your stitching the two lines together is more ringing from
> the via inductance, more crosstalk from the mutual inductance, and a slight
> increase in Zo. The impedence seen by either separate drivers or a single
> driver driving the two lines will be 70 ohms.

No. The impedance for two lines of 70 Ohm n parallel WILL BE 35 Ohm.

> .....For example, you may not be able to source that
> much current with the present driver, and may need to go to an AC
> termination scheme, or you might have to switch to a stronger driver, or you
> might have to do both.

Again: AC termination requires more peak driving current from driver than split
DC one - the "pre-history" helps driver to put up just half the necessary peak
driving current, while in AC termination for unbalanced signal (it is however
different for balanced signals, like clocks) requires full swing.

Dr. Johnson's book elaborates on this well....

Salvador:

If your skew is not that important (I understand, your signal is not GHz, but
somewhat slower) and you can afford few tens of picoseconds - than everything
you have to do is provide paths of reasonably equal lengths of 70 Ohms each,
each one referenced to the same GND Plane from different sides; this way you
eliminate mutual coupling and will get practically 35 Ohm Ch. Impedance.
If you use different GND planes - do not forget to provide return path GND via
when jumping layers.
The via reflection may not be that bad.

Also: If you know your driver output impedance and can match it to create source
termination for your 35 Ohm line - and you are point-to-point (no stubs etc) -
than just drop end terminator, use only source and you are going to get full
swing signal et thet end of your traces.

Mike.

> If you are doing an engineering look see, this
> should get you there, but I wouldn't recommend it for a manufactured
> product.
> Ken
>
> -----Original Message-----
> From: owner-si-list@silab.eng.sun.com
> [mailto:owner-si-list@silab.eng.sun.com]On Behalf Of
> Salvador_Aguinaga@3com.com
> Sent: Tuesday, October 31, 2000 11:26 AM
> To: Ken Cantrell
> Cc: si-list@silab.eng.sun.com
> Subject: RE: [SI-LIST] : Parallel single-ended traces routed to achieve
> 35 Ohm controlledimpedance
>
> Hello Ken,
>
> We have developed clock-driver circuit that benefits from low impedance
> lines.
> We have tested it in our older system and works well. We decided to add a
> test
> trace to our new backplane and test the circuit on the new system down the
> line.
> The backplane's primary design constraints (no. of layers, dielectric
> material &
> thickness, trace geometry, etc.) were dictated by other application
> requirements
> and performance objectives. So, now we want to fit this trace (if possible)
> and
> our board house is recommending we run two 70 Ohm traces in parallel. I
> just
> want to make sure we do this right --once.
>
> You are incorrect in quickly assuming there was not enough upfront design to
> do
> this right. Remember that every time you design a PCB one places priority
> on
> different parts or aspects of your design and normally other constraints
> come
> into play (over-all thickness, SI of other more important nets, pcb cost,
> fabrication issues, etc., etc.). You know where I'm going with this....
>
> All I ask for is: Would some one like to share their knowledge (and results)
> in
> regards to routing a 70 ohm trace on one set of layers and another of the
> same
> type on a different set of layers so tha when connected at the ends (and in
> between at even intervals) so that their parrallel impedance is 35 Ohms?
>
> Picture this (SIDE VIEW):
> _________________________________________ GND Layer
> dielectric material
> +=========+=========+===========+ <-----Signal layer 70 ohm impdance
> trace
> | | | |
> | | | | dielectric material
> _ | _______ | _______ | _________ | _____ GND Layer
> | | | |
> +=========+=========+===========+ <-----Signal layer 70 ohm impdance
> trace
> \
> vias dielectric material
> _________________________________________ GND Layer
>
> "Ken Cantrell" <Ken.Cantrell@srccomp.com> on 10/31/2000 10:18:06 AM
>
> Sent by: "Ken Cantrell" <Ken.Cantrell@srccomp.com>
>
> To: Salvador Aguinaga/MW/US/3Com, "Michael Nudelman"
> <mnudelman@tellium.com>
> cc: si-list@silab.eng.sun.com
> Subject: RE: [SI-LIST] : Parallel single-ended traces routed to achieve 35
> Ohm
> controlledimpedance
>
> Sounds like the cart is before the horse. I would ask why 35 ohms in the
> first place. Then if that is a valid requirement, you need to design your
> stack up so that you will get 35 ohms across all layers of the board. If
> other signals require a Zo of 70 ohms, and these particular traces require
> 35 ohms, it sounds like there was not enough upfront design going on during
> layout. Going back to the drawing board may be the fastest way to resolve
> your problem.
> -----Original Message-----
> From: owner-si-list@silab.eng.sun.com
> [mailto:owner-si-list@silab.eng.sun.com]On Behalf Of
> Salvador_Aguinaga@3com.com
> Sent: Friday, October 27, 2000 2:28 PM
> To: Michael Nudelman
> Cc: si-list@silab.eng.sun.com
> Subject: Re: [SI-LIST] : Parallel single-ended traces routed to achieve
> 35 Ohm controlledimpedance
>
> I need to run the trace through the a pin field. The room between pins is
> 2mm
> and because of the dielectric thickness constraint I can only run a single
> 12
> mil wide line through the pin field. If I use a single 35 ohm line, the
> trace
> width is too large to fit through the pin field.
>
> Thanks,
> -- Sal
>
> Michael Nudelman <mnudelman@tellium.com> on 10/27/2000 03:10:31 PM
>
> Sent by: Michael Nudelman <mnudelman@tellium.com>
>
> To: Salvador Aguinaga/MW/US/3Com
> cc: si-list@silab.eng.sun.com
> Subject: Re: [SI-LIST] : Parallel single-ended traces routed to achieve 35
> Ohm
> controlledimpedance
>
> **** To unsubscribe from si-list or si-list-digest: send e-mail to
> majordomo@silab.eng.sun.com. In the BODY of message put: UNSUBSCRIBE
> si-list or UNSUBSCRIBE si-list-digest, for more help, put HELP.
> si-list archives are accessible at http://www.qsl.net/wb6tpu
> ****
>
> **** To unsubscribe from si-list or si-list-digest: send e-mail to
> majordomo@silab.eng.sun.com. In the BODY of message put: UNSUBSCRIBE
> si-list or UNSUBSCRIBE si-list-digest, for more help, put HELP.
> si-list archives are accessible at http://www.qsl.net/wb6tpu
> ****

**** To unsubscribe from si-list or si-list-digest: send e-mail to
majordomo@silab.eng.sun.com. In the BODY of message put: UNSUBSCRIBE
si-list or UNSUBSCRIBE si-list-digest, for more help, put HELP.
si-list archives are accessible at http://www.qsl.net/wb6tpu
****


About this list Date view Thread view Subject view Author view

This archive was generated by hypermail 2b29 : Tue May 08 2001 - 14:29:55 PDT