RE: [SI-LIST] : RE: 2.5 GHz in FR4

About this list Date view Thread view Subject view Author view

From: Michael Nudelman (mnudelman@tellium.com)
Date: Mon Apr 30 2001 - 06:43:33 PDT


VCC and GND are equally noisy. And are equally good references. Imagine -
all your ref planes are VCCs. And just one is GND. What has changed?
Nothing.
 
The difference though is: if you use VCC/GND pairs as ref planes for each
hi-speed routing layer, you will have to put bunch of de-coupling capacitors
all over the board to provide for return currents along signals' runs i/o
putting bunch of vias connecting GNDs together.
 
What is more expensive I do not know. But the inductance of a cap as a
return path (cap itself and two vias) is higher than inductance of one via.
 
 
Mike.

-----Original Message-----
From: Javin Olson [mailto:Javin.Olson@plexus.com]
Sent: Monday, April 30, 2001 9:15 AM
To: si-list@silab.eng.sun.com
Subject: FW: [SI-LIST] : RE: 2.5 GHz in FR4

Richard,
 
Your comment about making the via act like a transmission line is correct.
There are 2 ways that I know of to remove the stub caused by a via:
 
Blind vias - via stub is completely removed, but fabrication cost is
doubled.
Counterboring - basically this method drills out the rest of the via, and it
adds about 25% to fabrication
 
Both methods obviously hurt the testability access to the board. The other
thing you can do is remove all non-functional pads within the via to reduce
the overall capacitance of the via.
 
I have one question about stripline and referencing in general: Is there a
benefit to having your high-speed diff-pair signal layers sandwiched between
2 GND layers? Are power layers generally a noisier reference?
 
Any thoughts on my last 2 questions would be appreciated...
 
Javin Olson
Plexus Technology Group
Design Engineer
   

-----Original Message-----
From: owner-si-list@silab.eng.sun.com
[mailto:owner-si-list@silab.eng.sun.com]On Behalf Of RMELLISON@aol.com
Sent: Monday, April 30, 2001 5:56 AM
To: ldmiller@rhapsodynetworks.com; mnudelman@tellium.com;
si-list@silab.eng.sun.com
Subject: Re: [SI-LIST] : RE: 2.5 GHz in FR4

Larry,
After reading all of the replies to the 2.5GHz questiion, I can see the need

for using stripline to keep phaseshift constant on long runs. In trying to
make the stubs a part of the transmission line, wouldn't it be advisable to
utilise most of the via as part of the line by using the stripline located
on
the opposite side of a card from the IC?
Consider the 8 layer stackup shown here for clarification.

------- Sig and IC layer
------------- Plane
------- Sig
------------- Plane
------------- Plane
------- Sig 2.5 GHz stripline
------------- Plane
------ Sig

The stub resulting from the the unused portion of the via is reduced in
length. The trick would be to make the vias look like the transmission line

impedance.

Another thought--It seems like an imbedded microstrip line would possess
almost the same qualities of a stripline in terms of dielectric affecting
phaseshift. Can a card be made so that the vias would go only from the IC
layer to an imbedded microstrip layer directly below? This would get rid of

any stubs. What do you think?

Richard Ellison
972-569-8317

**** To unsubscribe from si-list or si-list-digest: send e-mail to
majordomo@silab.eng.sun.com. In the BODY of message put: UNSUBSCRIBE
si-list or UNSUBSCRIBE si-list-digest, for more help, put HELP.
si-list archives are accessible at http://www.qsl.net/wb6tpu
****


About this list Date view Thread view Subject view Author view

This archive was generated by hypermail 2b29 : Thu Jun 21 2001 - 10:11:46 PDT